You can apply a concentrated force load to a vertex or node.
To create or edit a concentrated force:
Display the concentrated force load editor using one of the following methods:
To create a new concentrated force load, follow the procedure outlined in “Creating loads,” Section 16.8.1 (Category: Mechanical; Types for Selected Step: Concentrated force).
To edit an existing concentrated force load using menus or managers, see “Editing step-dependent objects,” Section 3.4.12. To edit the region to which the load is applied, see “Editing the region to which a prescribed condition is applied,” Section 16.8.4.
In the CF1, CF2, and CF3 text fields, enter the components of the concentrated force in each direction (units F):
If you leave a text field blank, a force of zero is assigned to that direction automatically. However, you must enter at least one nonzero component in the editor to define the load.
If desired, click the arrow to the right of the Amplitude field, and select the amplitude of your choice from the list that appears. Alternatively, you can click Create to create a new amplitude. (See Chapter 38, “The Amplitude toolset,” for more information.)
If desired, toggle on Follow nodal rotation to make the direction of the load rotate with the rotation at this node.
Follow nodal rotation affects only nodes that have rotational degrees of freedom and steps in which the Nlgeom setting is turned on.
If you want to change the coordinate system (CSYS) for the concentrated force load, click Edit and use one of the following methods:
Select an existing datum coordinate system in the viewport.
Select an existing datum coordinate system by name.
From the prompt area, click Datum CSYS List to display a list of datum coordinate systems.
Select a name from the list, and click OK.
Click Use Global CSYS from the prompt area to revert to the global coordinate system.
Click OK to save your data and to exit the editor.
