Product: ABAQUS/Explicit
This verification problem demonstrates characteristics of kinematic contact and penalty contact in ABAQUS/Explicit. The problem investigates the dynamic response of a truss impacting a rigid wall. The analysis is completed with a coarse and a refined mesh as shown in Figure 1.3.15–1 and Figure 1.3.15–2, respectively.
The truss has a length L=2 m and a cross-sectional area A=0.2 m2. Boundary conditions act on the truss nodes to allow horizontal motion only, reducing the problem to one dimension. For the coarse mesh the truss is discretized using five T2D2 elements; 10 elements are used for the refined mesh analysis. The truss is made of steel, with Young's modulus of E=200 GPa, Poisson's ratio of 
=0.3, and density of 
=7800 kg/m3. The material remains linearly elastic. The initial velocity of the truss is 
=1.5 m/s toward the rigid wall. The rigid wall is modeled using one R2D2 element. The wall is held in a fixed position. An initial clearance of 0.001 m between the truss and the wall is considered (see Figure 1.3.15–3); impact should occur at 6.67 × 10–4s.
The analytical solution predicts that the kinetic energy of the truss will be converted entirely to strain energy as the truss is compressed during impact; this strain energy will then be converted entirely back to kinetic energy as the truss rebounds, so the truss will leave the wall with a uniform velocity of 1.5 m/s. After the initial contact is established, a stress wave will travel along the truss at a rate of 
=5064 m/s. The analytical solution for the duration of the impact is 
=7.9 × 10–4 s, during which time the contact force remains at a constant value of F = 
=11.8 × 106 N. The momentum change of the truss corresponds to the contact force multiplied by the impact duration: 
=9.36 kg m/s.
Two approaches are used to model the contact between the leading truss node and the rigid wall. In the first approach contact is defined using the default kinematic contact formulation in ABAQUS/Explicit. The second approach uses MECHANICAL CONSTRAINT=PENALTY on the *CONTACT PAIR option to invoke the penalty contact formulation. The default penalty stiffness is used. The differences in these two contact formulations are discussed in greater detail in “Contact formulation for ABAQUS/Explicit contact pairs,” Section 29.4.4 of the ABAQUS Analysis User's Manual, and in the results section that follows.
Verification for this problem is provided by comparing the values of significant problem variables with the analytical solution. The numerical solutions are based on the default time incrementation except where noted.
Plots of kinetic energy are shown in Figure 1.3.15–4. Four stages of the solution (pre-impact, truss compression, truss re-expansion, and post-impact) are apparent in this plot. When penalty contact is used, the latter stages are delayed and changes in the slope at the transitions between these stages are smoothed. The onset of truss compression is advanced in time by one increment with kinematic contact. In each of the numerical solutions the kinetic energy is not entirely recovered upon rebound because of the numerical dissipation of energy and finite discretization. For the penalty contact solutions the dissipation of energy is primarily caused by small amounts of bulk viscosity (included by default in the ABAQUS/Explicit element formulations) and viscous contact damping (included by default for penalty contact). For the kinematic contact solutions both the bulk viscosity and the contact algorithm itself contribute significantly to the loss of energy. The kinematic contact algorithm dissipates the kinetic energy of the contact node upon impact, whereas the penalty contact algorithm converts the kinetic energy of the contact node into energy stored in the stretched penalty spring. These energy transfer considerations will be discussed further in the following paragraphs.
Velocity histories of the leading truss node (contact node) are plotted in Figure 1.3.15–5. The kinematic contact solutions for velocity closely match the analytical solution during pre-impact and during impact. The impact stage is less distinct in the velocity plots for penalty contact because some penetration occurs. All numerical solutions for the post-impact velocity show some oscillations that are not part of the analytical solution. These oscillations are associated with the energy dissipation and finite discretization. In the kinematic contact solutions a stress wave continues to pass through the truss during the post-impact phase, which periodically reduces the magnitude of the nodal velocity. This wave becomes narrower as the mesh is refined. With penalty contact a post-impact stress wave persists, which causes the post-impact nodal velocity to oscillate about approximately –1.5 m/s, where the negative velocity indicates movement in the negative x-direction. In all numerical solutions these velocity oscillations become more diffuse over time as a result of the bulk viscosity damping.
Contact force history solutions are plotted in Figure 1.3.15–6. For the kinematic contact tests ABAQUS/Explicit gives very good estimates of the peak contact force and captures the steps in the contact force history quite well. However, it will be shown later that the contact force history with kinematic contact depends on the size of the time increment used in the analysis. The penalty contact force solutions produce reasonable estimates of the peak contact force, but because of the inherent numerical softening of the penalty method, extreme mesh refinement is needed to observe sudden jumps in contact force.
Figure 1.3.15–7 contains plots of external work. The external work remains zero in the analytical solution. Some external work associated with contact forces, which are treated as external forces in ABAQUS/Explicit, can be observed in the numerical solutions. With penalty contact the external work accounts for the energy stored in the penalty springs during contact penetration and the energy dissipated by viscous contact damping. After the rebound the external work returns to a constant negative value as the penalty spring energy is recovered; the negative value corresponds to the amount of dissipation due to viscous contact damping. With kinematic contact a contact force first occurs in the increment just prior to the actual impact when a gap is still present; thus, penetration does not occur in the next increment. Therefore, the kinematic contact force does some work when contact is first established. This work corresponds to the kinetic energy of the contact node, and this energy is dissipated by the contact algorithm and is not recovered upon the rebound.
The energy dissipation caused by the bulk viscosity is plotted in Figure 1.3.15–8. This dissipation is greater with kinematic contact than with penalty contact because impacts in the kinematic contact formulation are not softened. Greater shock to the elements and increased element damping occur. Energy continues to dissipate after the rebound as a result of damping of stress waves that persist in the truss after the rebound.
Plots of strain energy are shown in Figure 1.3.15–9. The energy stored in penalty springs is not included in the strain energy reported by ABAQUS/Explicit, because the contact forces are treated as external forces. Instead, the energy stored in penalty springs appears as negative external work, as mentioned previously. Some strain energy remains after the rebound in the numerical solutions, which is related to stress waves that remain in the truss.
An undesirable characteristic of the kinematic contact algorithm is that the initial impact force predicted for a given mesh over the contact region depends on the size of the time increment. The contact force results shown in Figure 1.3.15–10 are based on analyses in which the time increment was scaled by 0.25 using the SCALE FACTOR parameter on the *DYNAMIC, EXPLICIT option. This scaling simulates the presence of a small element in the model that would control the time increment size. The kinematic contact algorithm will overestimate impact forces if the time increment is significantly lower than the stable time increments of elements near the contact region. Reducing the time increment causes the contact force to increase, because the approach speed of the leading node must be resolved over a shorter time interval to avoid penetration upon impact. Figure 1.3.15–10 also shows that the time increment size has negligible influence on the contact force solution if the penalty contact formulation is used. Other solution variables discussed in this example have minimal dependence on the size of the time increment for both types of contact constraint methods.
To better understand these results, consider a single slave node impacting a fixed rigid wall. Figure 1.3.15–11 and Figure 1.3.15–12 show such a contact slave node as a circle in increment . Friction will not be considered.
In the kinematic contact formulation ABAQUS/Explicit calculates a predicted penetration 
(see Figure 1.3.15–11). This predicted penetration is equal to the movement of the node if no contact condition is enforced. ABAQUS/Explicit then calculates the contact force, 
, in the normal direction according to
+1, the node contacts the surface of the opposing body without penetration (see Figure 1.3.15–11) and the loss of kinetic energy occurs. Although not shown in Figure 1.3.15–11, a contact force will also occur in increment +1 in the case of kinematic contact to eliminate the remainder of the velocity component normal to the surface.Figure 1.3.15–12 shows the schematic for the penalty contact formulation. The contact force is first applied in increment +1, and some penetration of the node into the opposing surface occurs. The contact force 
is calculated according to
is the penetration velocity. The penalty stiffness term can be envisioned physically as a spring attached between the penetrating node and the surface being penetrated. The energy is stored in this spring and is released as the node penetration reverses and decreases to zero (see Figure 1.3.15–7). The small amount of kinetic energy lost (see Figure 1.3.15–4) is the result of viscous effects of the elements, viscous contact damping, and strain energy remaining in the truss after separation (see Figure 1.3.15–9). As the mesh is refined, both formulations tend toward the analytical solution.Analysis of the refined model using the penalty contact formulation.
Analysis of the refined model using the kinematic contact formulation.
Analysis of the coarse model using the kinematic contact formulation.
Analysis of the coarse model using the penalty contact formulation.
Analysis of the refined model using the penalty contact formulation and a scaled time increment.
Analysis of the refined model using the kinematic contact formulation and a scaled time increment.
Analysis of the coarse model using the kinematic contact formulation and a scaled time increment.
Analysis of the coarse model using the penalty contact formulation and a scaled time increment.
