Products: ABAQUS/Standard ABAQUS/Explicit ABAQUS/CAE
You can define the element's initial constitutive thickness. The default initial constitutive thickness of cohesive elements depends on the response of these elements. For continuum response, the default initial constitutive thickness is computed based on the nodal coordinates. For traction-separation response, the default initial constitutive thickness is assumed to be 1.0. For response based on a uniaxial stress state, there is no default; you must indicate your choice of the method for computing the initial constitutive thickness. See “Specifying the constitutive thickness” in “Defining the cohesive element's initial geometry,” Section 26.5.4, for details.
ABAQUS calculates the thickness direction automatically based on the midsurface of the element.
| Input File Usage: | *COHESIVE SECTION |
| ABAQUS/CAE Usage: | Property module: Create Section: select Other as the section Category and Cohesive as the section Type |
Distributed loads are specified as described in “Distributed loads,” Section 27.4.3.
Load ID (*DLOAD): BR
ABAQUS/CAE Load/Interaction: Body force
Units: FL–3
Description: Body force in radial direction.
Load ID (*DLOAD): BY
ABAQUS/CAE Load/Interaction: Body force
Units: FL–3
Description: Body force in axial direction.
Load ID (*DLOAD): BRNU
ABAQUS/CAE Load/Interaction: Body force
Units: FL–3
Description: Nonuniform body force in radial direction with magnitude supplied via user subroutine DLOAD in ABAQUS/Standard and VDLOAD in ABAQUS/Explicit.
Load ID (*DLOAD): BZNU
ABAQUS/CAE Load/Interaction: Body force
Units: FL–3
Description: Nonuniform body force in axial direction with magnitude supplied via user subroutine DLOAD in ABAQUS/Standard and VDLOAD in ABAQUS/Explicit.
Load ID (*DLOAD): CENT(S)
ABAQUS/CAE Load/Interaction: Not supported
Units: FL–4(ML–3T–2)
Description: Centrifugal load (magnitude is input as 
, where 
is the mass density per unit volume, 
is the angular velocity).
Load ID (*DLOAD): CENTRIF(S)
ABAQUS/CAE Load/Interaction: Rotational body force
Units: T–2
Description: Centrifugal load (magnitude is input as 
, where is the angular velocity).
Load ID (*DLOAD): GRAV
ABAQUS/CAE Load/Interaction: Gravity
Units: LT–2
Description: Gravity loading in a specified direction (magnitude is input as acceleration).
Load ID (*DLOAD): Pn
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–2
Description: Pressure on face n.
Load ID (*DLOAD): PnNU
ABAQUS/CAE Load/Interaction: Not supported
Units: FL–2
Description: Nonuniform pressure on face n with magnitude supplied via user subroutine DLOAD in ABAQUS/Standard and VDLOAD in ABAQUS/Explicit.
Load ID (*DLOAD): SBF(E)
ABAQUS/CAE Load/Interaction: Not supported
Units: FL–5T2
Description: Stagnation body force in radial and axial directions.
Load ID (*DLOAD): SPn(E)
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–4T2
Description: Stagnation pressure on face n.
Load ID (*DLOAD): VBF(E)
ABAQUS/CAE Load/Interaction: Not supported
Units: FL–4T
Description: Viscous body force in radial and axial directions.
Load ID (*DLOAD): VPn(E)
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–3T
Description: Viscous pressure on face n, applying a pressure proportional to the velocity normal to the face and opposing the motion.
Surface-based distributed loads are specified as described in “Distributed loads,” Section 27.4.3.
Load ID (*DSLOAD): P
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–2
Description: Pressure on the element surface.
Load ID (*DSLOAD): PNU
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–2
Description: Nonuniform pressure on the element surface with magnitude supplied via user subroutine DLOAD in ABAQUS/Standard and VDLOAD in ABAQUS/Explicit.
Load ID (*DSLOAD): SP(E)
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–4T2
Description: Stagnation pressure on the element surface.
Load ID (*DSLOAD): VP(E)
ABAQUS/CAE Load/Interaction: Pressure
Units: FL–3T
Description: Viscous pressure applied on the element surface. The viscous pressure is proportional to the velocity normal to the element face and opposing the motion.
Stress, strain, and other tensor components available for output depend on whether the cohesive elements are used to model adhesive joints, gaskets, or delamination problems. You indicate the intended usage of the cohesive elements by choosing an appropriate response type when defining the section properties of these elements. The available response types are discussed in “Defining the constitutive response of cohesive elements using a continuum approach,” Section 26.5.5, and “Defining the constitutive response of cohesive elements using a traction-separation description,” Section 26.5.6.
Stress and other tensors (including strain tensors) are available for elements with continuum response. Both the stress tensor and the strain tensor contain true values. For the constitutive calculations using a continuum response, only the direct through-thickness and the transverse shear strains are assumed to be nonzero. All the other strain components (i.e., the membrane strains) are assumed to be zero (see “Modeling of an adhesive layer of finite thickness” in “Defining the constitutive response of cohesive elements using a continuum approach,” Section 26.5.5, for details). All tensors have the same number of components. For example, the stress components are as follows:
S11 | Direct membrane stress. |
S22 | Direct through-thickness stress. |
S33 | Direct membrane stress. |
S12 | Transverse shear stress. |
Stress and other tensors (including strain tensors) are available for cohesive elements with uniaxial stress response. Both the stress tensor and the strain tensor contain true values. For the constitutive calculations using a uniaxial stress response, only the direct through-thickness stress is assumed to be nonzero. All the other stress components (i.e., the membrane and transverse shear stresses) are assumed to be zero (see “Modeling of gaskets and/or small adhesive patches” in “Defining the constitutive response of cohesive elements using a continuum approach,” Section 26.5.5, for details). All tensors have the same number of components. For example, the stress components are as follows:
S22 | Direct through-thickness stress. |
Stress and other tensors (including strain tensors) are available for elements with traction-separation response. Both the stress tensor and the strain tensor contain nominal values. The output variables E, LE, and NE all contain the nominal strain when the response of cohesive elements is defined in terms of traction versus separation. All tensors have the same number of components. For example, the stress components are as follows:
S22 | Direct through-thickness stress. |
S12 | Transverse shear stress. |
, 
)
