To display X–Y plots of viscoelastic material behavior:

From the main menu bar, select MaterialEvaluatematerial name. The material that you select must include time domain viscoelastic material data defined in conjunction with hyperelastic and/or elastic material data.

Tip:  You can also select the name of the material in the Material Manager and then click Evaluate.

An Evaluate Material dialog box appears.

If you selected a viscoelastic material that also includes hyperelastic material data, click on the Viscoelastic tab; and toggle on Perform viscoelastic evaluation if it is not already selected.

If desired, you can also evaluate the hyperelastic behavior of the material. For more information, see “Displaying X–Y plots of hyperelastic material behavior,” Section 12.6.7.

In the Available Input Data field, do the following:

Select the Source option of your choice:

Select Test data if you want ABAQUS to calculate the creep and relaxation coefficients from the experimental data specified in the material definition.

Select Coefficients if you want ABAQUS to use the coefficients specified in the hyperelastic or elastic material definition.

If you selected Test data in the previous step, toggle on the test data type that you want ABAQUS to use in calculating the creep and relaxation coefficients. (Only data types for which you have specified data in the material definition appear in the list.)

Note:  Combined data cannot be selected at the same time as Shear or Volumetric data.

In the Normalized Response Plots field, select Stress Relaxation and/or Creep to define the response modes that ABAQUS will calculate.

For each test that you select, enter the time period for the normalized response curves.

Click OK to begin the response calculations.

If the evaluation fails during the extraction of material coefficients due to problems with nonlinear curve-fitting, ABAQUS/CAE displays a dialog box containing the name of the data (.dat) file; the path to the data file is printed in the message area. The data file provides detailed information on each problem encountered. (For more information on the data file, see “Output,” Section 4.1.1 of the ABAQUS Analysis User's Manual.)

If ABAQUS completes the tests successfully, ABAQUS/CAE enters the Visualization module and displays X–Y plots of the test results in new viewports. (For information on X–Y plots, see Chapter 30, “X–Y plotting.”) The data objects appear in the X–Y Data Manager; you can copy them to an output database or perform any of the tasks that you can perform on other X–Y data in the Visualization module.

In addition, ABAQUS/CAE displays an informational dialog box containing the viscoelastic material parameters and the stability limits and coefficients for each hyperelastic strain energy potential if a hyperelastic evaluation was performed. ABAQUS/CAE also displays in the message area the path to the data (.dat) file that contains all the material evaluation information.

If desired, return to the Property module to edit the material data or to evaluate other materials.