This option is used to impose constraints between different degrees of freedom of the model.
Products: ABAQUS/Standard ABAQUS/Explicit
Type: Model data
Level: Part Part Instance Assembly
Set this parameter equal to the name of the alternate input file containing the data lines for this option. See “Input syntax rules,” Section 1.2.1 of the ABAQUS Analysis User's Manual, for the syntax of such file names. If this parameter is omitted, it is assumed that the data follow the keyword line.
This parameter applies only to ABAQUS/Standard analyses.
This parameter is used only if the USER parameter is included. It is discussed further in “MPC,” Section 25.2.13 of the ABAQUS Analysis User's Manual.
Set MODE=DOF (default) for the subroutine to operate in a degree of freedom mode.
Set MODE=NODE for the subroutine to operate in a nodal mode.
This parameter applies only to ABAQUS/Standard analyses.
Include this parameter to indicate that the constraint is defined in user subroutine MPC.
First line:
MPC type from “General multi-point constraints,” Section 20.2.2 of the ABAQUS Analysis User's Manual, or, if the USER parameter is included, an integer key to be used in user subroutine MPC to distinguish between different constraint types.
Node numbers or node sets involved in the constraint.
The first 15 nodes or node sets of an MPC must be entered on the first line. If the MPC contains more than 15 nodes, enter 0 on the next line to indicate that it is a continuation line and then continue to enter the following nodes on this line. Any number of continuation lines are allowed. Exactly 15 nodes or node sets must be given on each line except the last line.